Path 3DSurface/fr

Description
Cet outil crée une nouvelle opération de surface 3D. L'opération Surface 3D utilise la surface supérieure entière du modèle 3D pour générer le G-Code pour le travail. Actuellement, dans les paramètres de l'opération, aucune fonctionnalité ne permet de sélectionner des zones, des faces ou des régions spécifiques de la base de tâches. L'opération est appliquée à la surface entière de la base des travaux.

L'outil 3D Surface s'interface avec OCL.pyd, un module Open Source tiers intitulé OpenCamLib, qui génère des chemins d'outil à partir d'un modèle 3D. OpenCamLib n'est pas directement intégré à FreeCAD. Les licences respectives sont respectées.

Remarque: pour utiliser l'opération Surface 3D, vous devez:
 * 1) Installer correctement OpenCamLib.
 * 2) Activez Fonctions expérimentales Path de l'atelier Path.

Utilisation
Les instructions d'utilisation pour plusieurs variantes de Surface 3D sont présentées ici.

Opération de base

 * 1) Appuyez sur l’icône  ou sélectionnez l’outil 3D Surface à partir du menut Path.
 * 2) Sélectionnez le contrôleur d'outil pour l'opération dans la fenêtre contextuelle du contrôleur d'outil.
 * 3) Ajustez les profondeurs d'opération selon vos besoins dans l'onglet Profondeurs: Début Profondeur, Fin Profondeur, Pas d'abaisse.
 * 4) Faites les ajustements nécessaires dans l’onglet Heights.
 * 5) Configurez les paramètres dans l'onglet Opérations:
 * 6) Sélectionnez un algorithme d'opération: OCL Dropcutter ou OCL Waterline.
 * 7) Choisissez le BoundBox: Stock ou BaseBoundBox.
 * 8) Ajouter des BoundBox Extra Offset supplémentaires à X et Y comme vous le souhaitez.
 * 9) Définissez la direction de la fraise: X ou Y. Il s’agit de la direction linéaire de la fraise (broche).
 * 10) Ajoutez une valeur de décalage de profondeur si vous souhaitez laisser une épaisseur de matériau spécifiée sur la surface.
 * 11) Définissez l'intervalle d'échantillonnage utilisé pour l'analyse OCL.
 * 12) Définissez la valeur de dépassement en tant que pourcentage du diamètre de l'outil.
 * 13) Optimiser la sortie est activé par défaut. Ce n'est qu'une optimisation de chemin linéaire. La désactivation donnera un résultat de gcode plus long et augmentera probablement le temps de coupe.
 * 14) Si vous souhaitez prévisualiser le résultat avant d'accepter les paramètres, cliquez sur Appliquer.
 * 15) Cliquez sur le bouton OK pour confirmer et générer les chemins.

To achieve different, or more complex, effects, adjust additional operation properties within the Data tab of the Properties View for the operation.

Multi-pass Scan
This variation is based on the property. It produces the layering effect - removing material in layers.
 * 1) Create a Basic Operation as described above. Multi-pass is available for both Algorithms.
 * 2) Select the new operation in the object tree in the Combo View.
 * 3) Locate the Algorithm section, In the Data tab in the Properties View of the operation.
 * 4) Toggle the  property to Multi-pass to achieve the layering(step-down, multi-pass) effect.

Rotational Scans (4th-axis)

 * 1) Create a Basic Operation as described above using the OCL Dropcutter algorithm.
 * 2) Locate the Data tab and Properties View for the new 3D Surface operation.It is recommended that you set the desired rotation properties all at once before recomputing. This is done by clicking the ENTER key immediately after changing a property setting. This process will allow you to change and save multiple properties before recomputing the operation.
 * 3) In the Rotation section set  to the correct setting.
 * 4) Adjust the following settings as needed:
 * 5) * In the Algorithm section, change to the axis of travel for the cutter(spindle).
 * 6) * In the Algorithm section, set to single or mulit-pass.
 * 7) * In the Rotation section, set to the desired axis.
 * 8) * In the Rotation section, adjust to start index(angle) [0-360].
 * 9) * In the Rotation section, adjust to stop index(angle) [0-360].
 * 10) * In the Rotation section, set to the offset index(angle) [0-90]. (Used for ball mill cutters)
 * 11) With rotation-related properties set as needed, in the Algorithm section change the  from Planar to Rotational.
 * 12) Click the  icon in the tool bar.
 * 13) Wait for the results...

Notes About Rotational Scans

 * Rotational scans require much more time and processing than Planar scans. Factors affecting processing time include: Sample Interval, Step Over, tool diameter, and model size.  Again, rotational scans can take a long time.  Some might take 3, 5 or 10 minutes or longer.
 * For time purposes, it is better that you not recompute a rotational scan after every property change; rather, consider one of the following:
 * use the ' change all settings with ENTER key ' technique mentioned in Step 2 above, then the operation.
 * deactivate the operation with the toggle tool, make your changes to the operation's properties, then click the  icon again to re-activate the operation - which triggers a recompute internally.
 * The operation is still considered an experimental feature as of 2019-06-25. As such, it may contain a few bugs yet to be clearly identified.  Please report bugs and issues in the FreeCAD Path/CAM Forum.
 * The OCL Waterline algorithm does not support rotational scans.
 * The built in does NOT support 4th-axis simulation.  You will need to use a third party simulator to inspect or verify paths visually.  See the Resources section below for suggestions.
 * You will likely see red rotational lines around your model in the viewport. This is normal in FreeCAD for the time being.

Available Tool (Cutter) Shapes
This 3D Surface op currently uses OpenCamLib [OCL] to extract paths from the part base. As such, a tool setting translation is required between the FreeCAD tool controller and OCL in order to complete the scan with your chosen tool(cutter) shape.

These tool shapes are respected and available for this 3D Surface operation:


 * End mill
 * Ball end mill
 * Bull nose end mill
 * Chamfer bit
 * Engraver

Should you choose to run the path simulator in the Path Workbench, it only uses the standard end mill to simulate paths. Therefore, you will not see tool-shape-specific material removal. Material removal is shown using the end mill shape. NOTE: As of May 2019, only the End Mill has any type of testing to determine accuracy of the FreeCAD-to-OCL tool settings translation. Please post any feedback for non-end-mill usage to the Path/CAM section in the FreeCAD forums.

Properties
 Note : Not all of these Properties are available in the Task Window Editor. Some are only accessible in the Data tab of the Properties View panel for this Operation.

Algorithm

 * : The library to use to generate the path
 * : Should the operation be limited by the stock object or by the bounding box of the base object
 * : The direction along which dropcutter lines are created
 * : Additional offset to the selected bounding box - use sub-properties to set values
 * : x distance value
 * : y distance value
 * : z distance value
 * : The completion mode for the operation: single or multi-pass
 * : Planar: Flat, 3D surface scan. Rotational: 4th-axis rotational scan.

Base
Note: It is suggested that you do not edit the Placement property of path operations. Rather, move or rotate the Path Job model as needed.


 * : Overall placement[position and rotation] of the object - with respect to the origin (or origin of parent object container)
 * : Angle in degrees applied to rotation of the object around Axis property value
 * : Axis(one or multiple) around which to rotate the object, set in sub-properties: x, y, z
 * : x axis value
 * : y axis value
 * : z axis value
 * : Position of the object, set in sub-properties: x, y, z - with respect to the origin (or origin of parent object container)
 * : x distance value
 * : y distance value
 * : z distance value
 * : User-provided name of the object (UTF-8)

Depth

 * : The height needed to clear clamps and obstructions
 * : Final Depth of Tool- lowest value in Z
 * : The above which Rapid motions are allowed.
 * : Starting Depth of Tool- first cut depth in Z
 * : Incremental Step Down of Tool

Path

 * : make False, to prevent operation from generating code
 * : An optional comment for this Operation
 * : The direction that the toolpath should go around the part: Climb(ClockWise) or Conventional(CounterClockWise)
 * : Defines the Tool controller used in the Operation
 * : Clearing pattern to use
 * : Identify cutter boundary for operation.
 * : User assigned label

Rotation

 * : Automatically attempt Inverse Angle if initial rotation is incorrect.
 * : Set the cutter (spindle) tilt angle.
 * : Enable rotation to gain access to pockets or areas not normal to Z axis.
 * : Set fixed index for rotation.
 * : Select indexing mode: auto = automatic angle detaction; fixed = user set angle.
 * : Inverse the angle of the rotation.   Example: change a rotation from -22.5 to 22.5 degrees.
 * : Reverse orientation of Operation by 180 degrees.
 * : Set the axis for model rotation.
 * : Start index(angle) for rotation
 * : Stop index(angle) for rotation
 * : Stop index(angle) for rotation

Surface

 * : Z-axis offset from the surface of the object
 * : Enable optimization which removes unnecessary points from G-Code output
 * : The Sample Interval. Small values cause long wait times
 * : Step over percentage of the drop cutter path

Waste

 * : Ignore areas that proceed below specified depth.
 * : Depth used to identify waste areas to ignore.
 * : Cut through waste to depth at model edge, releasing the model.

Tasks Window Editor Layout
Descriptions for the settings are provided in the Properties list above. This section is simply a layout map of the settings in the window editor for the Operation.

Base Location

 * Add: adds selected element(s) which should be the base(s) for the path(s)
 * Remove: remove the selected item(s) in the Base Location list
 * Edit: clear all items in the Base Location list

Resources

 * G-code(path) simulator: NCViewer
 * G-code(path) simulator: CAMotics